# Update PCB from schematic

<kbd>F8</kbd> compares the board with the schematic and shows what it would change before it changes anything. Footprints are matched to symbols the way KiCad matches them.

## Run it

1. Press <kbd>F8</kbd>, or choose **Update PCB** in the PCB view's toolbar. A count on the button shows how many footprints there are to update or add. <kbd>F8</kbd> works from any view and switches to the PCB.
2. Read the **Update PCB from schematic** panel. If there is nothing to do, it says "The board matches the schematic."
3. Choose **Update PCB** to apply it, or **Cancel**.

The update is one edit, so one undo reverts all of it.

## What it changes

The panel lists the changes in up to three groups:

- **Update footprints:** each footprint whose fields or pad nets differ from its symbol, with the changes: references, values, other fields, and the net of each pad.
- **Add footprints:** symbols that have no footprint on the board yet. Their footprints come from KiCad's footprint libraries and are lined up beside the board, packed by their courtyards, ready to place.
- **Footprints without a symbol:** footprints on the board that no symbol matches. They are kept unless you tick **Delete them**.

Footprints are matched to symbols by symbol path first, then by reference, as KiCad does.

![The Update PCB from schematic panel listing the footprint and net changes it will make.](https://crossprobe.ai/docs-media/update-pcb.webp "The changes are listed before anything is written. Shown: JDM COM84 PIC programmer, a KiCad demo project (GPL-2.0-or-later).")

## Parts without a footprint

A new part needs a footprint before Update PCB can place it. If some have none, the panel says how many and offers **Assign footprints…**, which opens the table of all parts with a chooser for each. See [fields and footprints](https://crossprobe.ai/docs/app/schematic-editing/#fields-and-footprints).

If a part's footprint isn't in the installed libraries, the update tells you which references it skipped. Set their **Footprint** field in the schematic and run it again.

## Check that the board is in sync

Differences between the schematic and the board are listed in the Issues tab under **Board ↔ schematic**, and the list updates after every edit. After an update, it has nothing left to report for the parts you changed.

A typical round trip on an existing project:

1. Change a part's value in the schematic.
2. Press <kbd>F8</kbd> and choose **Update PCB**.
3. Refill the zones with <kbd>B</kbd>.
4. Save with <kbd>⌘S</kbd>.

On KiCad's own pic_programmer demo, this leaves the schematic different from the original by exactly the one changed line, and KiCad reports the board in sync with the schematic.

> **Next:** place the new footprints and route them. See [PCB editing](https://crossprobe.ai/docs/app/pcb-editing/) and [Routing](https://crossprobe.ai/docs/app/routing/).
